End Mill Size Chart: How to Choose Diameter, LOC and OAL
August 28, 2026An end mill size chart identifies nominal cutting diameters. Choosing a usable tool also requires its shank diameter, length of cut (LOC), overall length (OAL) and, for recessed features, neck geometry. A matching diameter alone does not establish holder fit or usable reach.
The tables below separate metric cutter sizes from fractional inch sizes. They are dimensional references, not a statement that every size is available in every ZHY series. Product drawings determine the actual dimensions and tolerances.
Metric End Mill Size Chart
Common metric end mill diameters include 1, 2, 3, 4, 5, 6, 8, 10, 12, 16 and 20 mm. Intermediate and miniature diameters also exist. The inch column is a conversion of the stated diameter, not the name of an interchangeable inch tool.
Fractional Inch End Mill Size Chart
These fractional diameters provide a reference for inch tool descriptions. Millimeter values are exact conversions using 1 in = 25.4 mm. For example, 1/4 in is exactly 6.35 mm; it is not a 6 mm cutter.
End Mill Dimensions: D, Shank Diameter, LOC and OAL
Letters vary between catalogs. In this guide, D means cutting diameter and d means shank diameter. A drawing takes precedence over an assumed letter convention.
LOC is a geometry dimension, not a recommended single-pass depth. Actual axial engagement depends on the tool, material, radial engagement and machining conditions. OAL also does not equal installed projection: part of the shank remains inside the holder.
How to Choose an End Mill Size for Slots and Inside Corners
For an internal vertical corner generated by a cylindrical cutter, nominal cutter radius is D/2. A 6 mm cutter therefore has a nominal 3 mm radius. A part requiring a 2 mm internal corner radius cannot be completed at that corner with the same 6 mm cutter. Access geometry, finish allowance and a suitable finishing path still matter when choosing a cutter that fits.
For a straight slot made in one full-width pass, nominal cutter diameter sets the nominal swept width. Actual slot width can differ through runout, deflection, tool tolerance and wear. A precision slot may instead use a cutter that permits separate wall finishing; its programmed path then determines width together with the actual cutting envelope.
Small end mill sizes help reach narrow features, but the setup becomes sensitive to runout and unsupported length. There is no single minimum diameter for all milling operations. A nominal diameter listed in a catalog is not a promise that it will machine any feature of the same width.
A Worked Slot and Corner Example
Suppose a pocket drawing calls for an 8 mm-wide channel and a 2 mm internal corner radius. An 8 mm cutter can nominally span the straight channel in one pass, but its 4 mm cutter radius cannot generate the specified corner. A cutter of 4 mm diameter or less satisfies the simple radius limit D/2 ≤ 2 mm; the final choice still needs room for the approach and finishing path.
A 4 mm cutter does not make the entire channel 4 mm wide when it follows separate paths along the two walls. The programmed tool centerline, actual cutting diameter and compensation determine the finished width. This is why the smallest feature constrains cutter access, while the toolpath determines how a wider pocket is cleared.
Small End Mill Sizes: Check the Setup Before Going Smaller
A miniature cutting head may sit on a much larger shank. Confirm the cutting diameter separately from the clamping diameter, and check the transition behind the head against the feature. Runout that seems small relative to a large cutter can be significant relative to a miniature edge. The size chart alone does not establish a minimum achievable slot width or a safe cutting depth.
Choosing LOC, Neck Clearance and Reach Together
Feature depth and cutting engagement are different requirements. A deep cavity does not automatically require flutes along its entire depth. If only the bottom region is being cut, a relieved neck can clear the wall behind a short cutting head, provided the tool drawing and cavity geometry allow it.
As a hypothetical example, consider a 20 mm-deep cavity with a 3 mm axial finishing band at its bottom. A 3 mm cutting band does not by itself justify specifying either 3 mm or 20 mm LOC: approach motion, remaining stock, wall clearance and the manufacturer's geometry determine the usable choice. The neck and holder need clearance along the entire access path.
Ball Nose and Corner Radius End Mill Dimensions
On a full-radius ball nose end mill, the nominal ball radius is half the nominal cutting diameter: a 6 mm ball nose has nominal R3 geometry. The effective diameter at the contact point can differ from 6 mm depending on cutting depth and tool orientation. The size chart identifies nominal diameter, not contact diameter for a speed calculation.
A corner radius end mill instead specifies an outside cutting diameter and a separate corner radius. For example, D6 with R0.5 is a 6 mm outside diameter with a 0.5 mm corner radius, not a 1 mm ball nose tool. These numbers are explanatory examples, not a ZHY stock listing.
Match the Dimensions to the Material and ZHY Tool Series
What to Include in a Tool Size Request
A request such as “6 mm carbide end mill” leaves important dimensions unspecified. A useful request connects the feature drawing with D, shank diameter, LOC, OAL, any neck dimensions and the intended end profile. Workpiece material and the operation then help identify an appropriate series rather than treating diameter as the entire specification.
End Mill Size Questions
Does a 6 mm end mill always have a 6 mm shank?
No. Cutting diameter and shank diameter are separate dimensions. A tool may use a shank that differs from its cutting head, particularly with miniature or relieved-neck designs. The tool drawing and holder requirements determine compatibility.
Is a nominal size the same as the measured cutting diameter?
Nominal size identifies the tool's designated diameter. Manufacturing tolerance, coating, wear and the measurement method affect the measured value. A nominal size chart cannot replace the tolerance shown for the specific tool.
Can OAL be used to calculate cutting depth?
No. OAL includes the clamped shank and other non-cutting sections. Usable depth also depends on LOC, relieved reach, installed projection, holder clearance and the operation.